Re: [CAD_CAM_EDM_DRO] Mach3 /Rhinocam problem

On Wed, 11 Mar 2009 14:15:08 -0700 (PDT), you wrote:

>Thanks for your reply!   I'm feeling kind of stupid right now!

Don't worry about it, it's sloppy code, I've pointed out the errors
below.

>Below is the code.  I edited the post processor as per instructions from people on Mecsoft and Mach 3 forums.  I have to be doing something wrong!  Every time it goes into the G81 it sets off the abnormal light.  Motion mode in the Gen Config is set to CV.
> 
> 
>G00 G49 G40.1 G17 G80 G50 G90G64

What's G40.1??

>G20
>(Standard Drill )

Good practice to stop spindle before toolchange!

>M6 T1

Needs G43 H1 after M6 T1

>M03 S4583
>G00 Z0.1250
>X2.0000 Y0.2810

No feedrate defined for drill cycle?

>G81 X2.0000 Y0.2810 Z-0.6722 R0.1
>G80
>G00 Z0.1250
>G81 X0.5000 Y0.2810 Z-0.6722 R0.1
>G80
>G00 Z0.1250
>(2 1/2 Axis Pocketing)
>M6 T2

Needs G43 H2

>M03 S4583
>X1.2737 Y0.7375

Don't rely on modal move after toolchange

>G01 Z0.0292 F10.0

^^
Double spaces before all the F commands causing bad character error.

>Z0.0042  F6.0
>X1.2723 Y0.7383 Z0.0039  F4.0
>X1.2656 Y0.7407 Z0.0026
>X1.2588 Y0.7423 Z0.0014
>X1.2518 Y0.7430 Z0.0001
>X1.2447 Y0.7427 Z-0.0011

The following works without errors here now, M30 needs a carriage return
after it to rewind and was added for testing.

G00 G49 G40 G17 G80 G50 G90 G64
G20
(Standard Drill )
M6 T1
G43 H1
M03 S4583
G00 Z0.1250
X2.0000 Y0.2810
F10
G81 X2.0000 Y0.2810 Z-0.6722 R0.1
G80
G00 Z0.1250
G81 X0.5000 Y0.2810 Z-0.6722 R0.1
G80
G00 Z0.1250
(2 1/2 Axis Pocketing)
M6 T2
G43 H2
M03 S4583
G0 X1.2737 Y0.7375
G01 Z0.0292 F10
Z0.0042 F6
X1.2723 Y0.7383 Z0.0039 F4.0
X1.2656 Y0.7407 Z0.0026
X1.2588 Y0.7423 Z0.0014
X1.2518 Y0.7430 Z0.0001
X1.2447 Y0.7427 Z-0.0011
M30


Steve Blackmore
--