RE: [CAD_CAM_EDM_DRO] EMC Lathe mode.

Actually, the only thing that keeps my old Miyano 7BC (I think that's when
it was built) from getting an EMC control is the spindle issue. I could
live without the feed per revolution, but not without the threading
capability.

If anyone has figured out how to do this, I'd love to know.

Also, how would one deal with a spindle gearbox? I have a high and a low
range with eight speeds per range.

Ethan


-----Original Message-----
From: Jon Elson [SMTP:elson@...]
Sent: Tuesday, October 02, 2001 1:55 PM
To: CAD_CAM_EDM_DRO@yahoogroups.com
Subject: Re: [CAD_CAM_EDM_DRO] EMC Lathe mode.

Brian Pitt wrote:

> this aint as easy as it might look at first
>
> the G-Code interpreter would need to be redone in some areas for a
> turning center ,many of the codes do different things and most lathes

have

> some extra canned cycles for rough turning and facing that will take

several

> passes and leave some stock for the finish pass
> often the parts finished profile is given in a subroutine and the control
> will run that section of code twice ,once to rough it down and again as
> a constant contouring finish pass (another canned cycle)

There are lots of modifications added by some builders, but, in fact, the
standard G-codes were developed so, that they would be universal.
The canned cycles are mostly different, but canned cycles are not a
standardized feature of G-code, and are meant to be used in a machine-
dependent manner.

>
> tool nose radius comp is done slightly differently and the
> standard 8 TNR vectors would need to be added to the tool table ,
> maybe in place of some of the extra work offsets (lathes only use one)
> also many lathes do not use M03 to change tools,you first move to
> a preset tool change position (X positive limit) and just use T020202
> (tool 2 , pocket 2 , offset 2) calling that tool with a 2nd offset would

be

> T020222

M03 is turn spindle clockwise. I don't know of any machine that uses
M03 for tool change. The T020202 you mention is also a non-standard
use of the tool word. A D word following the T word provides the correct
offsets for the selected tool.

> the default cutting plane for arcs will need to be set to XZ rather than
> the mills default of XY (naturally)
>
> the spindle encoder should have a fairly high resolution both for

threading

> and as the C axis ,the encoder is often driven from a small timing belt

pulley

> separate from the spindle drive pulleys
> in fact most mills have a spindle encoder for rigid tapping and tool

indexing

> during tool changes
> so you should really think of the spindle as a full blown rotary axis on

ANY

> machine tool not just the lathe
> oh yea, even with a high resolution encoder at several thousand RPM the
> encoder counts will only be coming in at a few hundred Khz ,this

shouldn't be

> a problem for a reasonably fast computer to keep up with

The computer does not need to take any action on individual encoder counts.
An encoder counter device does that task. The computer only inquires
periodically what the count is, and computes where the Z (and possibly X
on tapered threads) should be.

One change is that the spindle is a 'recycling' axis, while other axes are
not. What I mean is that every so many counts, the spindle is back at
the same position. Some systems arrange for the spindle encoder counter to
reset back to zero every time the index mark comes up. The STG board,
and all others that use the LS7166 and LS7266 encoder counters can't
do this. So, the software needs to compensate for this effect, that the
spindle
counter just keeps counting revolution after revolution.

>
> constant surface speed was already mentioned
>
> and I don't remember if EMC has a feed per rev setting or just feed per

min

This would be the G33 word.

Jon


Addresses:
FAQ: http://www.ktmarketing.com/faq.html
FILES: http://groups.yahoo.com/group/CAD_CAM_EDM_DRO/files/

Post messages: CAD_CAM_EDM_DRO@yahoogroups.com
Subscribe: CAD_CAM_EDM_DRO-subscribe@yahoogroups.com
Unsubscribe: CAD_CAM_EDM_DRO-unsubscribe@yahoogroups.com
List owner: CAD_CAM_EDM_DRO-owner@yahoogroups.com, wanliker@...
Moderator: jmelson@... timg@... [Moderator]
URL to this page: http://groups.yahoo.com/group/CAD_CAM_EDM_DRO
bill,
List Manager



Your use of Yahoo! Groups is subject to http://docs.yahoo.com/info/terms/